DEMO_febio_0040_propeller_contact

Below is a demonstration for:

Contents

Keywords

clear; close all; clc;

Plot settings

fontSize=15;
faceAlpha1=0.8;
faceAlpha2=0.3;
markerSize=40;
lineWidth=3;

Control parameters

% Path names
defaultFolder = fileparts(fileparts(mfilename('fullpath')));
savePath=fullfile(defaultFolder,'data','temp');

% Defining file names
febioFebFileNamePart='tempModel';
febioFebFileName=fullfile(savePath,[febioFebFileNamePart,'.feb']); %FEB file name
febioLogFileName=fullfile(savePath,[febioFebFileNamePart,'.txt']); %FEBio log file name
febioLogFileName_disp=[febioFebFileNamePart,'_disp_out.txt']; %Log file name for exporting displacement
febioLogFileName_strainEnergy=[febioFebFileNamePart,'_energy_out.txt']; %Log file name for exporting strain energy density

% Propeller
% pointSpacing=6;

% Bar
barRadius=20;

% Define prescribed rotation
prescribedRotation_Z=pi/2;

% Material parameter set
c1=1e-3; %Shear-modulus-like parameter
m1=2; %Material parameter setting degree of non-linearity
k_factor=25; %Bulk modulus factor
k=c1*k_factor; %Bulk modulus
g1=1/2; %Viscoelastic QLV proportional coefficient
t1=12; %Viscoelastic QLV time coefficient
d=1e-9; %Density (not required for static analysis)

% FEA control settings
numTimeSteps=50; %Number of time steps desired
max_refs=25; %Max reforms
max_ups=0; %Set to zero to use full-Newton iterations
opt_iter=12; %Optimum number of iterations
max_retries=5; %Maximum number of retires
dtmin=(1/numTimeSteps)/100; %Minimum time step size
dtmax=(1/numTimeSteps); %Maximum time step size
symmetric_stiffness=0;
min_residual=1e-20;

%Contact parameters
contactPenalty=1;
laugon=0;
minaug=1;
maxaug=10;
fric_coeff=0.5;

Creating model geometry and mesh

% Import STL surface model
fileName=fullfile(defaultFolder,'data','STL','propeller.stl');
[stlStruct] = import_STL(fileName);

% Access the data from the STL struct
F=stlStruct.solidFaces{1}; %Faces
V=stlStruct.solidVertices{1}; %Vertices

% Merging nodes
[F,V]=mergeVertices(F,V);

% Remeshing and labelling
pointSpacing=10;
[Fp,Vp,Cp]=triRemeshLabel(F,V,pointSpacing);

% % Import STL surface model
% fileName=fullfile(defaultFolder,'data','libSurf','propeller_3.mat');
% importedMesh=load(fileName);
% Fp=importedMesh.F;
% Vp=importedMesh.V;
% Cp=importedMesh.C;

% Shift around mean
Vp=Vp-mean(Vp,1);

w=max(abs(max(Vp,[],1)-min(Vp,[],1))); %Width measure

pointSpacing=mean(patchEdgeLengths(Fp,Vp));

Creating triangulated bar mesh

optionStruct.cylRadius=barRadius;
optionStruct.numRadial=round((2*pi*barRadius)/(pointSpacing/2));
optionStruct.cylHeight=w/2;
% optionStruct.numHeight=optionStruct.numRadial;
optionStruct.meshType='tri';
optionStruct.closeOpt=1;
[Fc,Vc]=patchcylinder(optionStruct);

%Shift bar
Vc(:,1)=Vc(:,1)-w/3;
Vc(:,2)=Vc(:,2)-w/3;

center_of_mass=mean(Vc,1);

Plotting model boundary surfaces and a cut view

hFig=cFigure;
title('Model boundary surfaces and labels','FontSize',fontSize);
gpatch(Fp,Vp,Cp,'k',faceAlpha1);
gpatch(Fc,Vc,'kw','k',faceAlpha1);

colormap(gjet(250)); icolorbar;
axisGeom(gca,fontSize);
camlight headlight;

drawnow;

Mesh using tetrahedral elements

stringOpt='-pq1.2AaY';

inputStruct.stringOpt=stringOpt;
inputStruct.Faces=Fp;
inputStruct.Nodes=Vp;
inputStruct.holePoints=[];
inputStruct.faceBoundaryMarker=Cp; %Face boundary markers
inputStruct.regionPoints=getInnerPoint(Fp,Vp); %region points
inputStruct.regionA=tetVolMeanEst(Fp,Vp); %Volume for regular tets
inputStruct.minRegionMarker=2; %Minimum region marker

% Mesh model using tetrahedral elements using tetGen
[meshOutput]=runTetGen(inputStruct); %Run tetGen

% Access model element and patch data
Fb=meshOutput.facesBoundary;
Cb=meshOutput.boundaryMarker;
V=meshOutput.nodes;
CE=meshOutput.elementMaterialID;
E=meshOutput.elements;

 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- TETGEN Tetrahedral meshing --- 04-Jun-2019 13:14:32
 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- Writing SMESH file --- 04-Jun-2019 13:14:32
----> Adding node field
----> Adding facet field
----> Adding holes specification
----> Adding region specification
--- Done --- 04-Jun-2019 13:14:32
--- Running TetGen to mesh input boundary--- 04-Jun-2019 13:14:32
Opening /mnt/data/MATLAB/GIBBON/data/temp/temp.smesh.
Delaunizing vertices...
Delaunay seconds:  0.005787
Creating surface mesh ...
Surface mesh seconds:  0.001597
Recovering boundaries...
Boundary recovery seconds:  0.002099
Removing exterior tetrahedra ...
Spreading region attributes.
Exterior tets removal seconds:  0.001373
Recovering Delaunayness...
Delaunay recovery seconds:  0.001166
Refining mesh...
Refinement seconds:  0.011901
Optimizing mesh...
Optimization seconds:  0.001079

Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.node.
Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.ele.
Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.face.
Writing /mnt/data/MATLAB/GIBBON/data/temp/temp.1.edge.

Output seconds:  0.012725
Total running seconds:  0.037839

Statistics:

  Input points: 1073
  Input facets: 2146
  Input segments: 3219
  Input holes: 0
  Input regions: 1

  Mesh points: 1526
  Mesh tetrahedra: 5871
  Mesh faces: 12815
  Mesh faces on exterior boundary: 2146
  Mesh faces on input facets: 2146
  Mesh edges on input segments: 3219
  Steiner points inside domain: 453

--- Done --- 04-Jun-2019 13:14:32
 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- Importing TetGen files --- 04-Jun-2019 13:14:32
--- Done --- 04-Jun-2019 13:14:32

Visualizing mesh using meshView, see also anim8

meshView(meshOutput);

Joining node sets

Fc=Fc+size(V,1); %Fixed element indices
V=[V;Vc;]; %Combined node sets

Plotting joined geometry

cFigure;
title('Joined node sets','FontSize',fontSize);
hold on;
gpatch(Fb,V,Cp,'k',faceAlpha1);
gpatch(Fc,V,'kw','k',faceAlpha1);
colormap(gjet(6)); icolorbar;
axisGeom(gca,fontSize);
camlight headlight;
drawnow;

Define contact surfaces

% The rigid master surface of the sphere
F_contact_master=Fc;

% The deformable slave surface of the slab
F_contact_slave=fliplr(Fb(ismember(Cb,[1:7]),:));

% Plotting surface models
cFigure; hold on;
title('Contact sets and normal directions','FontSize',fontSize);

gpatch(Fb,V,'kw','none',faceAlpha2);
hl(1)=gpatch(F_contact_master,V,'gw','k',1);
patchNormPlot(F_contact_master,V);
hl(2)=gpatch(F_contact_slave,V,'bw','k',1);
patchNormPlot(F_contact_slave,V);

legend(hl,{'Master','Slave'});

axisGeom(gca,fontSize);
camlight headlight;
drawnow;

Define boundary conditions

%Supported nodes
F_shaft=Fb(Cb==11,:);
bcSupportList=unique(F_shaft);

Visualize BC's

hf=cFigure;
title('Boundary conditions model','FontSize',fontSize);
hold on;

gpatch(Fb,V,'kw','none',faceAlpha2);
gpatch(Fb(Cb==11,:),V,'rw','k',1);

clear hl;
hl(1)=plotV(V(bcSupportList,:),'k.','MarkerSize',markerSize);
legend(hl,{'BC support'});

axisGeom(gca,fontSize);
camlight headlight;
drawnow;

Defining the FEBio input structure

See also febioStructTemplate and febioStruct2xml and the FEBio user manual.

%Get a template with default settings
[febio_spec]=febioStructTemplate;

%febio_spec version
febio_spec.ATTR.version='2.5';

%Module section
febio_spec.Module.ATTR.type='solid';

%Control section
febio_spec.Control.analysis.ATTR.type='static';
febio_spec.Control.time_steps=numTimeSteps;
febio_spec.Control.step_size=1/numTimeSteps;
febio_spec.Control.time_stepper.dtmin=dtmin;
febio_spec.Control.time_stepper.dtmax=dtmax;
febio_spec.Control.time_stepper.max_retries=max_retries;
febio_spec.Control.time_stepper.opt_iter=opt_iter;
febio_spec.Control.max_refs=max_refs;
febio_spec.Control.max_ups=max_ups;
febio_spec.Control.symmetric_stiffness=symmetric_stiffness;
febio_spec.Control.min_residual=min_residual;

%Material section
febio_spec.Material.material{1}.ATTR.type='Ogden';
febio_spec.Material.material{1}.ATTR.id=1;
febio_spec.Material.material{1}.c1=c1;
febio_spec.Material.material{1}.m1=m1;
febio_spec.Material.material{1}.c2=c1;
febio_spec.Material.material{1}.m2=-m1;
febio_spec.Material.material{1}.k=k;

% %Viscoelastic part
% febio_spec.Material.material{1}.ATTR.type='uncoupled viscoelastic';
% febio_spec.Material.material{1}.ATTR.Name='Block_material';
% febio_spec.Material.material{1}.ATTR.id=1;
% febio_spec.Material.material{1}.g1=g1;
% febio_spec.Material.material{1}.t1=t1;
% febio_spec.Material.material{1}.density=d;
%
% %Elastic part
% febio_spec.Material.material{1}.elastic{1}.ATTR.type='Ogden';
% febio_spec.Material.material{1}.elastic{1}.c1=c1;
% febio_spec.Material.material{1}.elastic{1}.m1=m1;
% febio_spec.Material.material{1}.elastic{1}.c2=c1;
% febio_spec.Material.material{1}.elastic{1}.m2=-m1;
% febio_spec.Material.material{1}.elastic{1}.k=k;
% febio_spec.Material.material{1}.elastic{1}.density=d;

febio_spec.Material.material{2}.ATTR.type='rigid body';
febio_spec.Material.material{2}.ATTR.id=2;
febio_spec.Material.material{2}.density=1e-9;
febio_spec.Material.material{2}.center_of_mass=mean(V(bcSupportList,:),1);

febio_spec.Material.material{3}.ATTR.type='rigid body';
febio_spec.Material.material{3}.ATTR.id=3;
febio_spec.Material.material{3}.density=1e-9;
febio_spec.Material.material{3}.center_of_mass=mean(Vc,1);

%Geometry section
% -> Nodes
febio_spec.Geometry.Nodes{1}.ATTR.name='nodeSet_all'; %The node set name
febio_spec.Geometry.Nodes{1}.node.ATTR.id=(1:size(V,1))'; %The node id's
febio_spec.Geometry.Nodes{1}.node.VAL=V; %The nodel coordinates

% -> Elements
febio_spec.Geometry.Elements{1}.ATTR.type='tet4'; %Element type of this set
febio_spec.Geometry.Elements{1}.ATTR.mat=1; %material index for this set
febio_spec.Geometry.Elements{1}.ATTR.name='Propeller'; %Name of the element set
febio_spec.Geometry.Elements{1}.elem.ATTR.id=(1:1:size(E,1))'; %Element id's
febio_spec.Geometry.Elements{1}.elem.VAL=E;

febio_spec.Geometry.Elements{2}.ATTR.type='tri3'; %Element type of this set
febio_spec.Geometry.Elements{2}.ATTR.mat=2; %material index for this set
febio_spec.Geometry.Elements{2}.ATTR.name='Propeller_shaft'; %Name of the element set
febio_spec.Geometry.Elements{2}.elem.ATTR.id=size(E,1)+(1:1:size(F_shaft,1))'; %Element id's
febio_spec.Geometry.Elements{2}.elem.VAL=F_shaft;

febio_spec.Geometry.Elements{3}.ATTR.type='tri3'; %Element type of this set
febio_spec.Geometry.Elements{3}.ATTR.mat=3; %material index for this set
febio_spec.Geometry.Elements{3}.ATTR.name='Bar'; %Name of the element set
febio_spec.Geometry.Elements{3}.elem.ATTR.id=size(F_shaft,1)+size(E,1)+(1:1:size(Fc,1))'; %Element id's
febio_spec.Geometry.Elements{3}.elem.VAL=Fc;

% -> NodeSets
febio_spec.Geometry.NodeSet{1}.ATTR.name='bcSupportList';
febio_spec.Geometry.NodeSet{1}.node.ATTR.id=bcSupportList(:);

% -> Surfaces
febio_spec.Geometry.Surface{1}.ATTR.name='contact_master';
febio_spec.Geometry.Surface{1}.tri3.ATTR.lid=(1:1:size(F_contact_master,1))';
febio_spec.Geometry.Surface{1}.tri3.VAL=F_contact_master;

febio_spec.Geometry.Surface{2}.ATTR.name='contact_slave';
febio_spec.Geometry.Surface{2}.tri3.ATTR.lid=(1:1:size(F_contact_slave,1))';
febio_spec.Geometry.Surface{2}.tri3.VAL=F_contact_slave;

% -> Surface pairs
febio_spec.Geometry.SurfacePair{1}.ATTR.name='Contact1';
febio_spec.Geometry.SurfacePair{1}.master.ATTR.surface=febio_spec.Geometry.Surface{1}.ATTR.name;
febio_spec.Geometry.SurfacePair{1}.slave.ATTR.surface=febio_spec.Geometry.Surface{2}.ATTR.name;

%Boundary condition section
% -> Fix boundary conditions
febio_spec.Boundary.fix{1}.ATTR.bc='x';
febio_spec.Boundary.fix{1}.ATTR.node_set=febio_spec.Geometry.NodeSet{1}.ATTR.name;
febio_spec.Boundary.fix{2}.ATTR.bc='y';
febio_spec.Boundary.fix{2}.ATTR.node_set=febio_spec.Geometry.NodeSet{1}.ATTR.name;
febio_spec.Boundary.fix{3}.ATTR.bc='z';
febio_spec.Boundary.fix{3}.ATTR.node_set=febio_spec.Geometry.NodeSet{1}.ATTR.name;

% -> Prescribed boundary conditions on the rigid body
febio_spec.Boundary.rigid_body{1}.ATTR.mat=3;
febio_spec.Boundary.rigid_body{1}.fixed{1}.ATTR.bc='x';
febio_spec.Boundary.rigid_body{1}.fixed{2}.ATTR.bc='y';
febio_spec.Boundary.rigid_body{1}.fixed{3}.ATTR.bc='z';
febio_spec.Boundary.rigid_body{1}.fixed{4}.ATTR.bc='Rx';
febio_spec.Boundary.rigid_body{1}.fixed{5}.ATTR.bc='Ry';
febio_spec.Boundary.rigid_body{1}.fixed{6}.ATTR.bc='Rz';

febio_spec.Boundary.rigid_body{2}.ATTR.mat=2;
febio_spec.Boundary.rigid_body{2}.fixed{1}.ATTR.bc='x';
febio_spec.Boundary.rigid_body{2}.fixed{2}.ATTR.bc='y';
febio_spec.Boundary.rigid_body{2}.fixed{3}.ATTR.bc='z';
febio_spec.Boundary.rigid_body{2}.fixed{4}.ATTR.bc='Rx';
febio_spec.Boundary.rigid_body{2}.fixed{5}.ATTR.bc='Ry';
% febio_spec.Boundary.rigid_body{2}.fixed{6}.ATTR.bc='Rz';

febio_spec.Boundary.rigid_body{2}.prescribed{1}.ATTR.bc='Rz';
febio_spec.Boundary.rigid_body{2}.prescribed{1}.ATTR.lc=1;
febio_spec.Boundary.rigid_body{2}.prescribed{1}.VAL=prescribedRotation_Z;

%Contact section
febio_spec.Contact.contact{1}.ATTR.surface_pair=febio_spec.Geometry.SurfacePair{1}.ATTR.name;
febio_spec.Contact.contact{1}.ATTR.type='sliding-elastic';
febio_spec.Contact.contact{1}.two_pass=1;
febio_spec.Contact.contact{1}.laugon=laugon;
febio_spec.Contact.contact{1}.tolerance=0.2;
febio_spec.Contact.contact{1}.gaptol=0;
febio_spec.Contact.contact{1}.minaug=minaug;
febio_spec.Contact.contact{1}.maxaug=maxaug;
febio_spec.Contact.contact{1}.search_tol=0.01;
febio_spec.Contact.contact{1}.search_radius=0.1;
febio_spec.Contact.contact{1}.symmetric_stiffness=0;
febio_spec.Contact.contact{1}.auto_penalty=1;
febio_spec.Contact.contact{1}.penalty=contactPenalty;
febio_spec.Contact.contact{1}.fric_coeff=fric_coeff;

%LoadData section
febio_spec.LoadData.loadcurve{1}.ATTR.id=1;
febio_spec.LoadData.loadcurve{1}.ATTR.type='linear';
febio_spec.LoadData.loadcurve{1}.point.VAL=[0 0; 1 1];

%Output section
% -> log file
febio_spec.Output.logfile.ATTR.file=febioLogFileName;
febio_spec.Output.logfile.node_data{1}.ATTR.file=febioLogFileName_disp;
febio_spec.Output.logfile.node_data{1}.ATTR.data='ux;uy;uz';
febio_spec.Output.logfile.node_data{1}.ATTR.delim=',';
febio_spec.Output.logfile.node_data{1}.VAL=1:size(V,1);

febio_spec.Output.logfile.element_data{1}.ATTR.file=febioLogFileName_strainEnergy;
febio_spec.Output.logfile.element_data{1}.ATTR.data='sed';
febio_spec.Output.logfile.element_data{1}.ATTR.delim=',';
febio_spec.Output.logfile.element_data{1}.VAL=1:size(E,1);

Quick viewing of the FEBio input file structure

The febView function can be used to view the xml structure in a MATLAB figure window.

febView(febio_spec); %Viewing the febio file

Exporting the FEBio input file

Exporting the febio_spec structure to an FEBio input file is done using the febioStruct2xml function.

febioStruct2xml(febio_spec,febioFebFileName); %Exporting to file and domNode

Running the FEBio analysis

To run the analysis defined by the created FEBio input file the runMonitorFEBio function is used. The input for this function is a structure defining job settings e.g. the FEBio input file name. The optional output runFlag informs the user if the analysis was run succesfully.

febioAnalysis.run_filename=febioFebFileName; %The input file name
febioAnalysis.run_logname=febioLogFileName; %The name for the log file
febioAnalysis.disp_on=1; %Display information on the command window
febioAnalysis.disp_log_on=1; %Display convergence information in the command window
febioAnalysis.runMode='external';%'internal';
febioAnalysis.t_check=0.25; %Time for checking log file (dont set too small)
febioAnalysis.maxtpi=1e99; %Max analysis time
febioAnalysis.maxLogCheckTime=3; %Max log file checking time

[runFlag]=runMonitorFEBio(febioAnalysis);%START FEBio NOW!!!!!!!!

 
%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%%
--- STARTING FEBIO JOB --- 04-Jun-2019 13:14:39
Waiting for log file...
Proceeding to check log file...04-Jun-2019 13:14:40
------- converged at time : 0.02
------- converged at time : 0.04
------- converged at time : 0.06
------- converged at time : 0.08
------- converged at time : 0.1
------- converged at time : 0.12
------- converged at time : 0.14
------- converged at time : 0.16
------- converged at time : 0.18
------- converged at time : 0.2
------- converged at time : 0.218531
------- converged at time : 0.237356
------- converged at time : 0.256416
------- converged at time : 0.275664
------- converged at time : 0.295063
------- converged at time : 0.314581
------- converged at time : 0.3341
------- converged at time : 0.350446
------- converged at time : 0.364676
------- converged at time : 0.376664
------- converged at time : 0.390255
------- converged at time : 0.405127
------- converged at time : 0.418911
------- converged at time : 0.433938
------- converged at time : 0.448965
------- converged at time : 0.464762
------- converged at time : 0.481399
------- converged at time : 0.498709
------- converged at time : 0.516556
------- converged at time : 0.534835
------- converged at time : 0.553457
------- converged at time : 0.572355
------- converged at time : 0.591474
------- converged at time : 0.610769
------- converged at time : 0.630172
------- converged at time : 0.649696
------- converged at time : 0.669292
------- converged at time : 0.68897
------- converged at time : 0.708697
------- converged at time : 0.728479
------- converged at time : 0.748305
------- converged at time : 0.76736
------- converged at time : 0.786605
------- converged at time : 0.806
------- converged at time : 0.825517
------- converged at time : 0.842994
------- converged at time : 0.860471
------- converged at time : 0.878339
------- converged at time : 0.896633
------- converged at time : 0.914927
------- converged at time : 0.933383
------- converged at time : 0.946493
------- converged at time : 0.960668
------- converged at time : 0.969428
------- converged at time : 0.9786
------- converged at time : 0.989939
------- converged at time : 0.99899
------- converged at time : 1
--- Done --- 04-Jun-2019 13:15:45

Import FEBio results

if runFlag==1 %i.e. a succesful run

    % Importing nodal displacements from a log file
    [time_mat, N_disp_mat,~]=importFEBio_logfile(fullfile(savePath,febioLogFileName_disp)); %Nodal displacements
    time_mat=[0; time_mat(:)]; %Time

    N_disp_mat=N_disp_mat(:,2:end,:);
    sizImport=size(N_disp_mat);
    sizImport(3)=sizImport(3)+1;
    N_disp_mat_n=zeros(sizImport);
    N_disp_mat_n(:,:,2:end)=N_disp_mat;
    N_disp_mat=N_disp_mat_n;
    DN=N_disp_mat(:,:,end);
    DN_magnitude=sqrt(sum(DN.^2,2));
    V_def=V+DN;
    V_DEF=N_disp_mat+repmat(V,[1 1 size(N_disp_mat,3)]);
    X_DEF=V_DEF(:,1,:);
    Y_DEF=V_DEF(:,2,:);
    Z_DEF=V_DEF(:,3,:);

    % Importing element strain energies from a log file
    [~,E_energy,~]=importFEBio_logfile(fullfile(savePath,febioLogFileName_strainEnergy)); %Element stresses

    %Remove nodal index column
    E_energy=E_energy(:,2:end,:);

    %Add initial state i.e. zero displacement
    sizImport=size(E_energy);
    sizImport(3)=sizImport(3)+1;
    E_energy_mat_n=zeros(sizImport);
    E_energy_mat_n(:,:,2:end)=E_energy;
    E_energy=E_energy_mat_n;

    C=faceToVertexMeasure(E,V,E_energy(:,:,end));

Plotting the simulated results using anim8 to visualize and animate deformations

    % Create basic view and store graphics handle to initiate animation
    hf=cFigure; %Open figure
    gtitle([febioFebFileNamePart,': Press play to animate']);
    hp1=gpatch(Fb,V_def,C,'k',1); %Add graphics object to animate
    hp1.FaceColor='interp';
    hp2=gpatch(Fc,V_def,'kw','none',0.5); %Add graphics object to animate

    axisGeom(gca,fontSize);
    colormap(gjet(250)); colorbar;
    caxis([0 max(E_energy(:))/40]);
    axis([min(X_DEF(:)) max(X_DEF(:)) min(Y_DEF(:)) max(Y_DEF(:)) min(Z_DEF(:)) max(Z_DEF(:))]);
    camlight headlight;

    % Set up animation features
    animStruct.Time=time_mat; %The time vector
    for qt=1:1:size(N_disp_mat,3) %Loop over time increments
        DN=N_disp_mat(:,:,qt); %Current displacement
        DN_magnitude=sqrt(sum(DN.^2,2)); %Current displacement magnitude
        V_def=V+DN; %Current nodal coordinates

        C=faceToVertexMeasure(E,V,E_energy(:,:,qt));

        %Set entries in animation structure
        animStruct.Handles{qt}=[hp1 hp1 hp2]; %Handles of objects to animate
        animStruct.Props{qt}={'Vertices','CData','Vertices'}; %Properties of objects to animate
        animStruct.Set{qt}={V_def,C,V_def}; %Property values for to set in order to animate
    end
    anim8(hf,animStruct); %Initiate animation feature
    drawnow;

end

GIBBON www.gibboncode.org

Kevin Mattheus Moerman, [email protected]

GIBBON footer text

License: https://github.com/gibbonCode/GIBBON/blob/master/LICENSE

GIBBON: The Geometry and Image-based Bioengineering add-On. A toolbox for image segmentation, image-based modeling, meshing, and finite element analysis.

Copyright (C) 2019 Kevin Mattheus Moerman

This program is free software: you can redistribute it and/or modify it under the terms of the GNU General Public License as published by the Free Software Foundation, either version 3 of the License, or (at your option) any later version.

This program is distributed in the hope that it will be useful, but WITHOUT ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or FITNESS FOR A PARTICULAR PURPOSE. See the GNU General Public License for more details.

You should have received a copy of the GNU General Public License along with this program. If not, see http://www.gnu.org/licenses/.

Published with MATLAB® R2019a